Use a dimensioned chamfer (for example “0.5 × 45°” or “C0.5”) or a radius (“R0.5”) when the edge shape matters for function, assembly or looks. For every other edge, give one general note that sets a size range, such as “Break all sharp edges 0.2–0.5 mm, no burrs”, or the ISO 13715 edge symbol with limits. What causes rejects is not the choice between these, but leaving the edge condition undefined.
Edges look like a detail, yet they decide whether an O-ring survives assembly, whether an anodized corner chips, and whether an inspector at goods-in passes or rejects a batch. This guide explains each way to call out an edge, what a machine shop actually does with each note, and what to write so the result matches what you pictured.
Three different things: chamfer, radius and edge break
A chamfer and a radius are defined geometry. They have a size, a tolerance and, for a chamfer, an angle, and they are inspected like any other feature. An edge break is the opposite: a deliberately undefined edge whose only job is to remove the sharp corner and the burr.
- Chamfer: use where a part must enter a bore, a thread must start cleanly, or a visible bevel is part of the design.
- Radius: use where stress concentration, hand feel, coating build-up or seal damage matters. Internal corners are radiused by the cutter anyway; external radii need a corner-rounding tool or a profile pass.
- Edge break: use for everything else. It is the cheapest option because the shop can choose the method — a small chamfer pass, a deburring tool or hand work.
How to write a chamfer callout
The usual metric form is size × angle, for example “0.5 × 45°”. The shorthand “C0.5” (common on JIS-style drawings and widely understood in Asian shops) also means a 45° chamfer with 0.5 mm legs. For angles other than 45°, always give both the length and the angle, and say which leg the length refers to.
- 0.5 × 45° or C0.5: both legs 0.5 mm. Give a tolerance or rely on the general tolerance block; ISO 2768 has its own small table for chamfer heights and radii.
- 1 × 30°: state whether 1 mm is measured along the axis or radially. On turned parts, an axial length with the angle from the axis is the most common reading.
- Chamfers on holes: a countersink is called out by its diameter and angle (for example “⌵ Ø8 × 90°”) rather than by a leg length, because the diameter is what you can measure.
- Thread entries: a 90° countersink to just over the major diameter protects the first thread on a tapped hole; on external threads a chamfer down to slightly below the minor diameter does the same.
ISO 13715: the edge symbol for undefined edges
ISO 13715 (first published 2000, current edition 2017) gives a graphical symbol for edges of undefined shape. The symbol carries a plus or minus sign and a size. A plus means material may stand outside the ideal edge — a burr on an external edge, or “passing” on an internal edge. A minus means material must be removed — an undercut, which on an external edge is any chamfer, radius or break. A ± sign allows either.
The value is a limit, not a nominal size. When only one value is given, the other limit is zero. Two stacked values give a range. The standard’s recommended sizes run from 0.02 and 0.05 mm through 0.1, 0.3, 0.5 and 1 mm up to 2.5 mm, in plus and minus.
- −0.3 on an external edge: no burr allowed; the edge may be broken by anything from zero up to 0.3 mm.
- −0.1 / −0.5 (two values): no burr; the edge must be broken by at least 0.1 mm and at most 0.5 mm. This is the closest equivalent to “break edges 0.1–0.5”.
- +0.3: a burr up to 0.3 mm is acceptable — useful for hidden edges where deburring adds cost and no value.
- ±0.05: a “sharp” edge, burr or break no larger than 0.05 mm either way. Expensive; use only where a sharp edge is functional.
- A collective indication near the title block applies to all edges not otherwise specified. External-only and internal-only collective forms exist too.
Writing a general edge note that inspectors can check
If your CAD template or customer base does not use ISO 13715, a text note works just as well — provided it has numbers. “Deburr” or “break all sharp edges” on its own cannot be measured, so the shop and your inspector will each apply their own idea of it.
- Good: “Unless otherwise specified, break all external edges 0.2–0.5 mm, chamfer or radius at the shop’s option. No burrs. Internal corners: cutter radius allowed.”
- Good: “All edges ISO 13715 −0.1/−0.4 unless otherwise specified.”
- Vague: “Deburr all edges”, “Remove sharp edges”, “Smooth finish” — no size, no acceptance limit.
- Exceptions: list edges that must stay sharp (sealing lands, cutting edges, datum corners) and mark them with their own symbol or note.
Where vague edge notes cause rejects
Most edge rejects fall into a few patterns. Each one is cheap to prevent on the drawing and expensive to fix after a batch is machined.
- Cross-holes and intersecting bores: burrs inside a part are hard to reach. Say whether internal intersections must be burr-free and how it will be checked.
- O-ring entry edges: an edge that is only “deburred” can still cut a seal. Bores and rods that an O-ring passes over need a dimensioned lead-in chamfer, typically 10–20° per the Parker O-Ring Handbook, and a smoothly blended edge.
- Mating faces: a large chamfer on a locating shoulder reduces the contact area and can move a bearing or flange off its datum. Keep breaks small on functional shoulders.
- Knife edges: where a chamfer meets a thin wall, a fixed C1 can leave a feather edge. Size chamfers relative to the wall.
Edges on parts that will be anodized
Anodic oxide grows roughly perpendicular to the surface, so at a sharp external corner the coating from the two faces does not join well. The result is a thin or crazed line that chips easily — more noticeable with hard anodizing, which is thicker and more brittle than Type II. A small radius, or a chamfer with its own edges lightly blended, gives a more even coating and fewer chipped corners.
- Specify edge breaks before finishing, as a machining requirement, and the coating on top.
- For hard-anodized parts, ask your finisher what edge radius they prefer; many request a small radius rather than a sharp chamfer.
- Burrs left under anodizing become hard and sharp. A clean edge before anodizing matters more than on a bare part.
Edges and deburring at Chi Xin
Chi Xin Technology is a CNC machine shop in Nantun District, Taichung, Taiwan, founded in 2022. We run 5+ CNC machines — 4.5-axis CNC machining centers and CNC lathes — and mainly machine aluminum alloys and alloy steel, with a metal tolerance of 0.02 mm. We also offer wire EDM and surface finishing including anodizing, and we export to customers in Europe and North America.
We machine and deburr aluminum and steel parts on our machining centers and lathes and handle anodizing as part of the job, so a clear edge note on your drawing — chamfer sizes, break range and sharp-edge exceptions — lets us quote and inspect the edges the way you intend.
Frequently asked questions
Is C0.5 the same as 0.5 × 45°?
Yes. The C prefix means a 45° chamfer whose two legs equal the number given, so C0.5 is a 0.5 mm × 45° chamfer. For any other angle, write the length and the angle explicitly.
What does “break sharp edges” mean if no size is given?
It means whatever the shop and the inspector think it means, which is why it causes disputes. Add a range such as 0.2–0.5 mm, or use the ISO 13715 symbol with limits, so the requirement can be measured.
Does ISO 13715 replace chamfer dimensions?
No. ISO 13715 is for edges of undefined shape. Where the edge has a defined form, such as a 1 × 45° chamfer for an assembly lead-in, it is dimensioned normally under ISO 129-1, and the edge symbol covers the remaining edges.
Should I put a radius or a chamfer on edges that will be hard anodized?
A small radius generally gives a more uniform coating and chips less than a sharp corner. Tell us the finish in the RFQ and we confirm the edge preparation in the quotation.
Do internal corners need an edge note?
Internal corners on milled pockets always have at least the cutter radius. If a corner must be sharper or have a specific radius, dimension it; otherwise the note can allow the cutter radius.



