A CNC milled aluminum enclosure is designed well when the pocket can be cut with a standard end mill in as few setups as possible: walls of roughly 1.5–3 mm, internal corner radii a little larger than the cutter, pocket depth no more than about 4 times the cutter diameter, and tight tolerances only on mating faces, bores and seal grooves. Most cost problems in machined housings come from breaking one of those rules without needing to.
This guide is for engineers designing housings for electronics, sensors, motor controllers, optics or instruments in 6061 or similar alloys. It goes feature by feature and ends with the notes worth putting on the drawing.
Start from the stock and the tool
A milled enclosure starts as a plate or bar block and most of it becomes chips. Two things set the price before any tolerance does: how much material is removed and how long the cutter has to be. Size the outside envelope close to a standard plate thickness, and size the inside so a short, rigid end mill can reach the floor.
Rough rule: an end mill cuts comfortably to about 3 times its diameter; 4 times is still practical, and beyond that the tool deflects, chatters and has to take light passes. A 60 mm deep pocket with 4 mm corner radii therefore forces a slow, long-reach tool, while the same pocket with 10 mm radii can be cleared with a 16–20 mm cutter.
Wall and floor thickness
Thin walls vibrate when they are cut and spring back afterwards, so their tolerance and finish suffer first.
- Metal walls down to roughly 0.5–0.8 mm are possible on short walls, but 1.5–3 mm is the comfortable range for housings in 6061.
- Keep wall height to roughly 10–15 times the wall thickness or less; tall thin walls need extra passes or support.
- Floors behave the same way: a large thin floor will bow when the pocket is cleared. Add ribs or bosses instead of thinning everything.
- Avoid knife edges where an outside chamfer meets an inside pocket; leave at least the minimum wall at the thinnest point.
- Constant wall thickness helps anodizing and heat flow look and behave evenly.
Internal corners, pockets and undercuts
A rotating cutter always leaves a radius in a vertical inside corner. Design for it instead of drawing sharp corners that a shop has to question.
- Make vertical inside radii slightly larger than the cutter radius (for example R5.5 for a 10 mm cutter) so the tool sweeps the corner instead of stopping in it.
- A common guideline is inside radius at least one third of the pocket depth.
- Floor-to-wall radius can be sharp (flat end mill) or a small fillet (bull-nose cutter); state which you need only if it matters for a PCB or a lid.
- If a square component or PCB must sit in the corner, use dog-bone or T-bone relief cuts rather than asking for a sharp corner.
- Undercuts, internal O-ring grooves on walls and lips need special cutters; ask whether a separate cover plate would avoid them.
Threads, inserts and fastening
Threads in aluminum strip if they are reused often or too short. Thread engagement of roughly 1.5–2 times the nominal diameter is a common rule for tapped aluminum; going beyond about 3 times adds little strength and makes tapping harder.
- Use standard metric (ISO 965) or unified (ASME B1.1) sizes and state the tolerance class only if you need something other than 6H / 2B.
- For lids opened in service, specify wire thread inserts or self-tapping/press-in inserts instead of bare threads.
- Leave a flat boss around tapped holes in thin walls so the thread has material on all sides.
- Blind holes need extra drill depth below the last full thread; give the full-thread depth, not just the drill depth.
- Remember that anodizing builds up on threads; mask them or tap after anodizing if fit is critical.
Gasket grooves and mating faces
For an IP-rated housing the seal is usually where the cost and the rejects are. Take groove width, depth and corner radius from the seal maker’s data (for O-rings, the supplier handbook gives face-seal groove dimensions for each cord size) and keep groove corners large enough for a standard small cutter.
The lid face and the body face need flatness and a roughness requirement, not a tight tolerance on every dimension. A flatness callout on the sealing face (per ASME Y14.5 or ISO 1101) and a roughness such as Ra 1.6 µm on that face only is usually enough; the rest of the part can follow general tolerances such as ISO 2768-m. Large thin lids can move after machining as stress is released, so state flatness for the finished part and let the shop plan roughing and finishing passes.
Anodizing, EMI and thermal details
Anodized aluminum is electrically insulating on the surface. That matters for grounding and EMI shielding: contact areas for earth screws, EMI gaskets and lid-to-body joints need masking before anodizing, or a conductive chemical conversion coating (MIL-DTL-5541 type) instead of anodizing on those faces.
- Break all outside edges (for example 0.2–0.5 mm chamfer or radius): anodize coats sharp edges thinly and they chip and look pale.
- Roughly half of an anodic layer grows outward from the original surface; allow for it on bores and fits.
- Mark masking areas on the drawing with a hatch and a note, not only in an email.
- For heat sinking, flat contact pads under hot components and a defined pad flatness do more than extra fins; ask for thermal pad areas to stay flat and unmasked if you use thermal interface material.
- Machine marks show through clear and colored anodize; say if cosmetic faces need a bead-blasted or uniform finish before anodizing.
Cost drivers and what to write on the drawing
The biggest cost drivers in a milled enclosure are the number of setups (each face with features is another orientation), deep pockets with small radii, tight tolerances applied everywhere, cosmetic requirements and masking. A housing with features on four sides benefits from a 4th-axis or 4.5-axis machine because several faces can be reached in one clamping.
- Material and temper (e.g. 6061-T6 / T651 plate)
- General tolerance standard plus specific tolerances on bores, mating faces and grooves
- Flatness and roughness on sealing and thermal faces
- Thread sizes, depths and inserts
- Finish, color, masking areas and cosmetic faces
- Edge break note and quantity per batch
Aluminum enclosures at Chi Xin
Chi Xin Technology is a CNC machine shop in Nantun District, Taichung, Taiwan, founded in 2022. We run 5+ CNC machines — 4.5-axis CNC machining centers and CNC lathes — and mainly machine aluminum alloys and alloy steel, with a metal tolerance of 0.02 mm. We also offer wire EDM and surface finishing including anodizing, and we export to customers in Europe and North America.
We mill aluminum housings, blocks and brackets on our 4.5-axis machining centers and can anodize them, so pocket design, masking and finish can be reviewed together when you send the drawing.
Frequently asked questions
What is the minimum wall thickness for a CNC aluminum enclosure?
Short walls can be machined down to roughly 0.5–0.8 mm, but 1.5–3 mm is a safer range for housings. Thinner walls vibrate during cutting, lose tolerance and dent easily.
Can you machine sharp internal corners in a pocket?
Not with a rotating cutter. Specify a radius slightly larger than the cutter radius, or add dog-bone relief cuts if a square part must fit. Truly sharp inside corners need wire EDM or sinker EDM, which adds cost.
Should I use 6061 or 7075 for an enclosure?
Most housings use 6061 because it machines well, anodizes evenly and is easy to source. 7075 makes sense only when the housing carries real structural loads and the anodized appearance is less important.
How do I keep an anodized enclosure grounded?
Mark grounding points and EMI gasket faces as masked areas on the drawing, or specify a conductive conversion coating on those faces. Tell us in the RFQ and we confirm the approach in the quotation.
Will a large lid stay flat?
Thin plates can bow after material is removed. Give flatness only on the sealing face, keep thickness reasonable, and let the shop rough and finish in separate steps to release stress.


